+91 8866188126 [email protected]

PCB design guide

Rigid-flex PCBs: construction, design rules and when to use them

A rigid-flex board joins firm circuit-board sections and bendable flexible layers into one laminated part, wired together without connectors or cables. This guide explains how they are built, when they are worth the extra cost, the layout rules that keep the rigid-to-flex boundary reliable, and what to send us for a rigid-flex quote.

Get an instant quote

What rigid-flex is — and how it differs from a flex board with stiffeners

Both look similar at first glance: hard areas where parts sit, connected by a bendable tail. The difference is what is inside the hard areas.

Rigid-flex

The flexible polyimide layers continue inside the rigid sections and are laminated together with glass-epoxy layers into one multilayer board. Plated through holes connect copper on the rigid layers to copper on the flex layers, so the rigid areas can carry many routing layers, buried connections and dense parts.

Flex with stiffeners

A one- or two-layer flex circuit with pieces of FR-4, polyimide or metal bonded to the back of selected areas. The stiffener only adds mechanical support — it carries no copper and no connections. All routing still happens in the thin flex layers.
AspectFlex + stiffenerRigid-flex
Routing layers in the hard areasSame as the flex (typically 1–2)As many as the rigid stackup needs (commonly 4 or more)
Electrical role of the hard areaNone — mechanical support onlyFull multilayer circuit board
Fine-pitch and dense partsPossible on small areasWell suited — the rigid section behaves like a normal multilayer board
Build complexityLower: flex build plus bondingHigher: several lamination cycles, mixed materials, controlled depth routing
Relative costLowerHigher, especially for small quantities
Typical useSimple sensors, LED strips, connector tails, displaysCompact multi-board products, wearables, medical and industrial devices, cameras, avionics-style designs

Quick answer

If the hard areas only need to hold a connector or a few parts and all wiring fits in one or two layers, a flex board with stiffeners is usually simpler and cheaper — see the flex PCB design guide. If the hard areas need multilayer routing of their own, rigid-flex is the right construction.

When rigid-flex makes sense

Rigid-flex costs more per board than separate rigid boards joined by a cable, so it pays off when it removes parts, failure points or space.

Fewer connectors and cables

Every board-to-board connector pair and cable adds parts, assembly steps and contacts that can loosen or corrode. Replacing them with continuous copper removes those failure points and the cost of the connectors.

Smaller and lighter products

Flex layers fold into the space available, so several rigid sections can be stacked or wrapped around an enclosure. Connector bodies and cable slack disappear, which saves height and weight.

Better vibration and shock behaviour

Without mating connectors there is nothing to fret or disconnect under vibration. This is a common reason for rigid-flex in vehicles, drones, industrial sensors and handheld equipment.

Cleaner signals between sections

Continuous traces with a defined stackup avoid the impedance steps and extra length of connectors, which helps high-speed and sensitive analogue links.

Simpler final assembly

One assembled part is folded and fitted instead of several boards plus harness. Fewer items to stock, wire and test.

When it does not pay off

Low-volume products with plenty of space, designs that change often, or boards that must be replaced separately in the field are usually better served by rigid boards plus a cable or a simple flex jumper.

Typical constructions

Rigid-flex stackups are described by how many layers there are in total, how many of them are flexible, and where the flex layers sit.

ConstructionHow it is builtWhere it fits
Flex core in the middleOne or two flex layers run through the centre of the stack; rigid glass-epoxy layers are laminated above and below them in the hard sections only.The most common and balanced arrangement. The symmetric stack helps keep the rigid areas flat.
Multiple separate flex layersTwo or more flex circuits pass through the rigid sections but are left unbonded to each other in the bend area (sometimes called an air-gap or loose-leaf construction).More flex routing layers while keeping each bending layer thin, so the bend stays flexible.
Flex on an outer layerThe flex layer forms the top or bottom of the rigid sections.Less common; can simplify some builds but makes the rigid stack asymmetric and more prone to bow and twist.
Asymmetric flex positionThe flex layers sit off-centre in the stack, for example to suit a fold direction or a shielding layer.Possible, but needs care with warpage and impedance; discuss it with the fabricator early.
Book-binder (staggered lengths)Each flex layer is made slightly longer than the one inside it so a stack of layers can bend around a tight radius without buckling.Many flex layers bent together; a specialised and costly build.

Naming a stackup

A common shorthand is the rigid layer count plus the flex layer count, for example "6-layer rigid-flex with 2 flex layers on L3–L4". Always back it up with a stackup drawing that lists every layer, material and thickness.

Keep the bend area simple

Only the layers that must cross the bend should be flexible. Ground planes, power and dense routing belong in the rigid sections, where extra layers do not stiffen the bend.

Stackup and impedance

Controlled-impedance traces on flex layers use different dielectric materials and often hatched reference planes, so the numbers differ from a standard FR-4 build. The basics of stackups and impedance are covered in stackup and impedance; for rigid-flex, ask for a stackup proposal from the fabricator before finishing your layout.

Rigid-to-flex transition zones

The line where a flex layer leaves the rigid section is the most stressed part of the board. Material changes, adhesive flow and bending all concentrate there.

  1. 1

    Keep plated holes away from the boundary

    Vias and plated through holes near the transition can crack when the flex section moves, and resin or adhesive flow around the edge makes drilling less predictable. A common rule of thumb is to keep plated holes at least about 1 mm (roughly 50 mil is often quoted) inside the rigid area, and more where space allows.

    Tip: Never place vias in the flex section of the bend zone itself.

  2. 2

    Keep components back from the edge

    Parts placed close to the transition are stressed whenever the flex moves, and the edge region may not be perfectly flat. Typically allow a few millimetres between the rigid edge and the nearest pad; leave more for large or heavy parts and for connectors that are plugged by hand.
  3. 3

    Cross the boundary at right angles

    Route traces straight across the transition, perpendicular to the rigid edge, so they bend evenly. Avoid corners, vias, width changes and pad connections in the first few millimetres of flex.
  4. 4

    Avoid hard copper edges along the boundary

    A solid copper pour that ends exactly on the transition line creates a stiffness step where cracks start. Stop planes short of the boundary or use hatched copper in the flex area, and stagger trace positions between flex layers instead of stacking them directly on top of each other.
  5. 5

    Add teardrops and generous widths

    Teardrops on pads and vias near the transition, and slightly wider traces through it, give the copper more material to share the strain.
  6. 6

    Consider strain relief

    For boards that will be folded often during assembly or service, a bead of flexible material along the rigid edge (a strain-relief fillet) spreads the bending load. Mark it on the drawing if you need it.

These are general guidelines, not guarantees

Exact clearances depend on the materials, layer count and the fabricator's process. Treat the values above as starting points and confirm them during the quote review. Design guidance for flex and rigid-flex boards is collected in IPC-2223, and acceptance of finished boards is commonly specified against IPC-6013.

Bend and fold areas

Decide early how the board will move. The answer changes the stackup, the copper type and the minimum bend radius.

Static (bend to install)Dynamic (bends in use)
Typical exampleFolded once to fit an enclosure, then fixedHinge, sliding mechanism, moving head or cable replacement that flexes in normal use
Layers crossing the bendOne or two (sometimes more with an unbonded construction)Ideally one copper layer, placed near the neutral axis of the bend
CopperStandard copper is often acceptableRolled-annealed copper is commonly preferred for its better fatigue life
Bend radiusTighter radii acceptableMuch larger radii needed
ValidationFold test on a sampleCycle testing in the real mechanism before volume orders

Bend radius rules

The usual rules of thumb relate minimum bend radius to total flex thickness and depend on layer count and static or dynamic use. They are explained in the flex PCB design guide and apply equally to the flex section of a rigid-flex board.

Start bends away from the rigid edge

Plan the bend to begin some distance into the flex section rather than right at the rigid edge, so the transition is not the hinge point. A few millimetres of straight flex before the bend is a common starting point.

Mark bend lines on the drawing

Show where and in which direction each bend happens, the bend radius and angle, and whether it is static or dynamic. This lets the fabricator choose materials and check that the stackup can bend as intended.

Coverlay, adhesive and bikini-cut construction

Flex layers are protected by coverlay rather than liquid solder mask, and the way coverlay and adhesive enter the rigid sections affects reliability.

Coverlay

A polyimide film with adhesive, laminated over the flex circuit with openings cut for pads. It is tougher and more flexible than solder mask. Openings are usually slightly larger than the pad, and pads near the opening edge benefit from anchoring tabs so they do not lift.

Adhesive-based vs adhesiveless laminates

Older and lower-cost flex materials bond copper to polyimide with an acrylic or epoxy adhesive. Adhesiveless laminates bond the copper directly; they are thinner, bend better and expand less with heat, which is why they are widely used in rigid-flex.

Bikini (selective) coverlay

Instead of running coverlay through the whole board, it is cut so it covers the flex area and overlaps only a short distance into the rigid section. This keeps soft, high-expansion adhesive out of the plated-hole areas of the rigid stack, which helps hole reliability through soldering heat.

Bonding rigid to flex

Rigid layers are typically joined to the flex core with low-flow or no-flow prepreg, so the resin does not run out onto the flex area during lamination. Expect a small region of resin squeeze-out at the transition and keep features out of it.

Polyimide absorbs moisture

Flex materials take up moisture from the air more readily than FR-4. Rigid-flex boards are commonly baked before reflow and kept sealed with desiccant until assembly to avoid delamination or blistering. Moisture-sensitive components are handled per J-STD-033; for bare boards, IPC-1601 gives general handling and storage guidance, and the fabricator's baking advice for the specific materials should be followed.

Assembling rigid-flex boards

Assembly uses the same steps as any SMT board — paste print, placement, reflow, inspection — but the flexible parts need support. The general flow is explained in how PCB assembly works.

  1. 1

    Deliver in a panel with the flex held flat

    Rigid-flex boards are usually built and shipped in a panel where the rigid frame and breakaway tabs hold every flex section flat. The panel must have rails and fiducials for the machines. We assemble boards in panels only — see the panel guide.

    Tip: Leave the flex sections attached to the panel until all soldering and inspection is finished.

  2. 2

    Use carriers or fixtures where needed

    Where the panel alone cannot hold the board flat, a carrier plate or fixture supports it during printing and reflow. Double-sided assembly may need a different fixture for each side.
  3. 3

    Dry the boards before reflow

    Because of moisture uptake in the flex layers, boards are commonly baked before the first reflow if they have been out of sealed packing.
  4. 4

    Inspect and test before folding

    Inspection to IPC-A-610 and electrical testing are easiest while the board is still flat in the panel. Fold or form the flex only after testing.
  5. 5

    Handle by the rigid areas

    During depanelling, folding and fitting, hold the rigid sections, not the flex. Use ESD-safe handling (ANSI/ESD S20.20 is the common reference) throughout.

Assembly at Microplacer

Our instant assembly price is calculated from solder pads, and components are quoted from your BOM. Boards with BGA, LGA or 0201 parts go to engineering review. For a rigid-flex design, mention it in your notes — our engineers check every file before production and will confirm the panel and support plan with you. See the assembly quote FAQ and design for assembly.

What to send us for a rigid-flex quote

Rigid-flex is quoted by our team. The instant online price covers FR-4 boards up to 16 layers and one- or two-layer flexible PCBs; for rigid-flex, send your files and drawing and we will come back with a price.

ItemWhat it should show
Gerber or ODB++ dataEvery copper layer, plus coverlay openings, solder mask for the rigid areas, silkscreen, stiffeners (if any) and a board outline. Mark which outline areas are rigid and which are flex.
Drill filesPlated and non-plated holes; buried or blind vias called out by layer pair.
Stackup drawingEach layer in order: copper weight, rigid and flex materials, prepreg, coverlay, and which layers run through the flex sections. Note any unbonded flex layers.
Fabrication drawingRigid and flex dimensions, bend lines, bend direction, radius and angle, static or dynamic use, and any strain relief or stiffeners.
Electrical requirementsImpedance targets with the reference layers, and any special test needs.
Finish and appearanceSurface finish, solder mask and silkscreen colours for the rigid areas, coverlay colour for the flex areas.
Quantity and panelNumber of boards and, if you have one, your preferred panel layout.
Assembly files (if needed)BOM and pick-and-place file as described in preparing your design files.
  1. 1

    Send the files

    Share the data and drawing through contact us. Write any production notes into the files or the drawing — we read them and compare them with the options we can offer.
  2. 2

    Engineering review

    Our engineers check the stackup, transitions and bend areas, and contact you if something needs to change before we price it.
  3. 3

    Quote and order

    You receive a quote for the agreed construction. Payment is made when you place the order, by online payment or bank transfer.

Could a flex board do the job?

If your design fits a one- or two-layer flex circuit, you can price the bare board instantly by choosing Flex in our online calculator. If it also needs stiffeners, mention them in your notes so our engineers can confirm them. See flex PCB capabilities for the options it offers.

Rigid-flex FAQ

Not yet. The instant price covers FR-4 boards up to 16 layers and one- or two-layer flexible PCBs. Rigid-flex designs are reviewed and quoted by our team — send your files and drawing and we will reply with a price.

Per board, usually yes, because the build needs more materials and lamination steps. Across the whole product it can cost less once you count the connectors, cable, assembly labour and the failures they cause, especially in higher volumes.

As few as possible. One or two flex layers are typical. Put planes and dense routing in the rigid sections, and use an unbonded construction if you need more layers to cross the bend while keeping it flexible.

Small parts can be placed on flex areas that do not bend, usually with a stiffener behind them. Keep parts out of bend zones and away from the rigid-to-flex transition. Pad anchoring and stiffener tips are in the flex PCB design guide.

Flat finishes such as ENIG are a common choice because they suit fine-pitch parts and the coverlay openings on flex areas. Compare finishes in the surface finish guide and tell us your preference with the quote request.

Design guidance for flex and rigid-flex is commonly taken from IPC-2223 (with IPC-2221 for general board design), board performance and acceptance from IPC-6013, and assembled-board workmanship from IPC-A-610. State the class you need on your drawing.

Yes. Our engineers check every set of files before production and contact you if anything in the stackup, transitions or panel needs to change.

Related guides

Still have a question?

Send us your files or call us — our engineers will help you choose the right options for your boards and assembly.

Streamline your innovation with seamless PCB ordering.

For More Details Contact Us