+91 8866188126 [email protected]

Flex PCB design guide

Flexible PCB design tips — boards that bend without breaking

A flex board can fold into tight enclosures, replace cables and survive movement — but only if the layout respects how thin copper behaves when it bends. This guide covers the design rules that matter most and the flex options you can price instantly with Microplacer.

Get an instant quote

How a flex board differs from a rigid board

The copper circuit is the same idea; the materials around it are not.

Rigid board (FR-4)Flexible board
Base materialGlass-fibre epoxy laminate — stiff and strong.Polyimide film — thin, heat resistant and able to bend.
Protective layerLiquid solder mask printed over the copper.Coverlay: a polyimide film with adhesive, laminated over the copper. Openings are cut where pads must stay exposed.
Typical thicknessAround 0.4–2.0 mm; 1.6 mm is the common standard.A fraction of a millimetre (see the table below).
Mechanical supportThe board holds itself and its parts.Needs stiffeners or a fixture under connectors and heavy parts.
Main design worryElectrical rules — spacing, current, signal integrity.Mechanical rules too — where it bends, how often and how tightly.

Coverlay is not solder mask

Coverlay is a film, so its openings are cut rather than printed. That makes very small, tightly spaced openings harder than on a rigid board. A common approach is to give each pad (or a group of fine-pitch pads) a slightly larger opening than you would use for solder mask, and to keep the coverlay edge away from places that will bend.

Flex options in our online calculator

Select Flex as the material on the Online PCB Quote page and the form switches to the options below. For the full capability table (tolerances, drill and trace limits) see Flex PCB capabilities.

OptionWhat you can choose online
Layers1 or 2 copper layers.
Thickness and copperThickness and copper weight come in fixed pairs.
1 layer: 0.07 mm (⅓ oz), 0.11 mm (½ oz), 0.12 mm (1 oz).
2 layers: 0.11 mm (⅓ oz), 0.12 mm (½ oz), 0.20 mm (1 oz).
Surface finishENIG (flat gold) only.
Coverlay colourGreen, red, yellow, blue, white, black or purple.
Maximum size600 × 250 mm (for a panel, this is the size of the whole panel).
QuantityFrom 5 boards, like our rigid PCBs.
Also availableCastellated holes, panels (by Microplacer or your own panel file), order-number removal or a 2D barcode.
Electrical test100% flying-probe test for opens and shorts — included free.

If you change the thickness, the copper weight follows automatically. Choose the thickness that matches the copper your design needs: thinner copper bends more easily, thicker copper carries more current.

Bend radius: how tightly can it bend?

The tighter the bend, the more the copper is stretched on the outside of the curve. Copper that is stretched too far — or too often — cracks.

Static flex (bend once, then stay)

The board is folded during installation and then stays in place — for example, folded to fit a housing. This is forgiving: tighter bends are acceptable because the copper is stressed only once or a few times.

Dynamic flex (bends again and again)

The board moves in normal use — a hinge, a moving print head, a sliding part. Each movement stresses the copper, so bends must be much gentler and the stack-up as thin and simple as possible.
SituationCommon rule of thumb for the minimum bend radius
1-layer, staticAbout 6 × the total flex thickness
2-layer, staticAbout 10–12 × the total flex thickness
1-layer, dynamicMuch larger — figures from about 20 × up to 100 × the total flex thickness are commonly quoted; use the high end for many bend cycles
2-layer, dynamicAvoid if you can — use a single-layer bend area instead

These are general guidelines, not guarantees

Real limits depend on copper weight, coverlay, adhesive and how often the board moves. For a moving application, build a few samples and test them in the real mechanism before ordering in quantity.

Quick example

A 2-layer flex of 0.12 mm folded once into a housing: 0.12 × 10 = 1.2 mm, so aim for a bend radius of at least about 1.2 mm — larger is always safer.

Routing in bend areas

Most flex failures start in the bend zone. A few layout habits prevent nearly all of them.

  1. 1

    Mark the bend zone on your drawing

    Decide early where the board will bend and draw that area on a mechanical or comment layer. Every rule below applies inside it.
  2. 2

    Run traces straight across the bend

    Traces should cross the bend line at 90°. A trace running at an angle or along the bend gets twisted and stretched unevenly.
  3. 3

    Use curves instead of sharp corners

    Change direction with smooth arcs rather than 90° or even 45° corners. Sharp corners concentrate stress and are where cracks begin.
  4. 4

    Stagger traces on 2-layer boards

    Do not place a trace on the top layer directly over a trace on the bottom layer in the bend zone. Offsetting them spreads the stress and keeps the bend thinner. For a plane in a bend area, a cross-hatched pour bends far more easily than solid copper.
  5. 5

    Keep vias, pads and parts out of the bend

    Plated holes and solder joints are stiff points that crack when flexed. Place vias, pads and components on the flat areas, ideally a few millimetres away from where the bend starts.

    Tip: Spread traces evenly across the width of the bend area. Many thin traces in one cluster with empty space beside them make the board bend unevenly.

  6. 6

    Keep the outline smooth

    Round inside corners of the board outline and avoid slots or notches that end in a sharp corner. A small relief hole at the end of a slot stops a tear from spreading.

Stop pads from lifting or cracking

Copper on polyimide holds less firmly than on FR-4, especially after soldering heat. Help each pad hold on.

Teardrops

Widen the trace where it meets a pad or via. The smooth transition removes the narrow neck where cracks usually start.

Anchor spurs (tie-downs)

Small copper extensions on a pad that tuck under the coverlay. The coverlay then holds the pad down, which helps single-layer boards with no plated holes.

Coverlay overlapping the pad edge

Size coverlay openings so the film just captures the edge of the pad (or its spurs). The pad stays fully solderable but is clamped at the sides.

Larger annular rings

Give through-holes a slightly larger copper ring than on a rigid board. Extra copper around the hole means a stronger joint.

Wider traces near pads

Thin traces are fine in the middle of a run, but widen them where they join pads and connectors — the place that sees the most handling.

Use the right copper weight

Thinner copper bends better; thicker copper carries more current. Choose the thinnest copper that safely carries your current.

Stiffeners: support where the board must not bend

A stiffener is a piece of rigid material bonded to the back of the flex, so one area stays flat and firm.

Where they are usedWhy
Under connectorsA plug is pushed in and pulled out; without support the copper under the connector pins flexes and cracks.
Under component areasSolder joints cannot bend. A stiffener keeps the area flat during assembly and in use.
ZIF / FFC contact fingersThe contact end of the flex must reach a fixed thickness to fit the socket and must be stiff enough to insert.
Mounting holesGives screws and clips something firm to clamp without tearing the film.
  1. 1

    Draw the stiffener outline

    Add each stiffener as a closed outline on its own mechanical layer, and say which side of the flex it goes on (usually the side opposite the components or contacts).
  2. 2

    State material and thickness

    Write the stiffener material and thickness you need. Common choices are polyimide (thin — often used to build up ZIF contact thickness), FR-4 (stiffer, used under parts and connectors) and stainless steel (thin but very stiff).
  3. 3

    For contacts, state the total thickness

    For a ZIF or FFC connector, give the finished thickness the connector datasheet asks for at the contact area. The stiffener is chosen so flex + stiffener reaches that value.
  4. 4

    Add it to your order

    Stiffeners are not an option in the online calculator. Put a short note in the PCB remark field, include the drawing in your Gerber zip, or send your files for a quote. Our engineers check your files before production and confirm whether the stiffeners can be supplied; if the price changes, we tell you first and you choose to pay the difference or cancel with a full refund.

Assembling parts on a flex board

Support the board during assembly

A flex board cannot hold itself flat for paste printing and placement. It is usually supported by stiffeners, a panel frame or a carrier. We assemble boards in panels only — see the panel guide.

Keep parts away from bend lines

Place components on flat, supported areas and leave a clear gap between the last part and the start of any bend.

Prefer smaller, lighter parts

Heavy or tall parts lever on their joints when the board moves. Put them over a stiffener or on a rigid board connected by the flex.

Orient parts along the bend

If a part must sit near a flexing area, align its long side parallel to the bend line so fewer joints are stretched.

Need assembly on your flex?

Upload your Gerber, BOM and pick-and-place files as usual and mention in your notes that it is a flex board. Our engineers review every file before production and contact you if the support or panel plan needs a change, or if the design cannot be assembled as drawn. More on the steps in How PCB assembly works.

What affects the price of a flex board

The online price already includes GST and shipping. These choices move it up or down.

Number of layers

A 2-layer flex needs more material and process steps than a 1-layer flex. If one layer can carry your circuit, it is the cheaper and more flexible choice.

Size and shape

Flex material cost generally scales with area. Long, thin or L-shaped outlines waste material around them, so nesting several boards in a panel often lowers the price per board.

Copper and thickness

Pick the thickness/copper pair you actually need; the calculator shows the price for each.

Stiffeners and extras

Stiffeners and other work the calculator does not cover are not in the online price. Our engineers review them and confirm any price change before production.

Not available on flex boards

These rigid-board options are hidden when you choose Flex: via covering choice (plugged or filled vias), small-via options, impedance control, gold fingers, material brand/TG and finishes other than ENIG. If your design needs them, consider a rigid board with a flex cable, or send your files for a quote.

Flex PCB FAQ

Yes. Upload your Gerber, choose Flex as the material and pick 1 or 2 layers, thickness and coverlay colour. The price appears instantly and includes GST and shipping.

5 boards, the same as for rigid PCBs.

ENIG gives a flat, thin and solderable surface that suits thin flex copper and fine-pitch parts. It is the only finish offered for flex in our calculator.

Stiffeners are not part of the online calculator. Draw them on a mechanical layer, note the material, thickness and side, and mention them in the PCB remark (or send your files for a quote). Our engineers check whether they can be supplied before production. If the price changes, you can accept the difference or cancel with a refund.

Yes. Every board gets a 100% flying-probe test for opens and shorts at no extra charge.

Bare PCBs are typically delivered in 10–15 working days in India, including express shipping. Orders that need an engineering review (for example, with stiffeners or assembly) may take longer — we confirm the timing with you.

Related guides

Still have a question?

Send us your files or call us — our engineers will help you choose the right options for your boards and assembly.

Streamline your innovation with seamless PCB ordering.

For More Details Contact Us